Assembly Pattern Data

Define the pattern data in the dialog box.

Dialog Box Options

Linear
Defines the pattern as linear. Click the Linear button. You can define a linear pattern in an assembly in either one direction or in both the longitudinal and latitudinal directions. For a linear pattern, define the number of components, either the length (width) or the distance, and the angle at which the components will be set.
Creating a Linear Pattern in One Direction
Creating a Linear Pattern in Both Directions
Selecting the Direction of a Linear Pattern in an Assembly
Polar
Defines the pattern as polar. Click the Polar button. For a polar pattern, define the number of components, the angle between components and the radius at which the components will be set.
Polar Pattern
Polar with pitch
Defines polar pattern with pitch. As an example, stairs.
Pitch
Defines the value of the pitch.
No rotation
An asymmetric component will be rotated in a polar pattern (default). You can prevent rotation of the component by selecting the No rotation check box.
With guide curves
Create a part pattern along a line or tangential line chain. Select lines to the Guide curves
list. Example: Strand
Locating point
Define a point from the part or assembly that is projected to the line. The default point is the part's or assembly’s origin or handle.
For best results, select a part’s or assembly’s point that is also on the curve.
Number
Defines the number of components in the pattern. The component based on which the pattern is created is included in the number of pattern components.
Formula
Defines a variable for a pattern property, for example number, length or width.
Length
The software calculates the line chain length.
Scale
Defines the distance (D) left between the components in either the longitudinal or latitudinal direction. Example: Define a linear pattern to both directions: 2 pieces of components, distance between them is 50.
Distance: With guide curves
If you entered a Delta value, you can choose whether the distance is calculated Along Curves or Straight.
Length
Defines the length value (L) in the longitudinal direction at which the components will be set at equal distances. The direction of the positive X axis determines the longitudinal direction in the assembly (default). To check the directions of the axes, press the K button to change the cursor into a coordinate axis cursor. If necessary, rotate the pattern.
Define a linear pattern to length’s direction: 5 pieces of components, the length is 120.
Width
Defines the width value (W) in the latitudinal direction at which the components will be set at equal distances. The direction of the positive Y axis determines the latitudinal direction in the assembly (default).
Define a linear pattern to width’s direction: 3 pieces of components, the width is 50.
Define a linear pattern in both the longitudinal and latitudinal directions (angle = 90 degrees).
You can define the latitudinal direction for a polar pattern, too.
Radius
The radius defines the value of the radius in the geometry, type of guide curve, PATTERNPOLAR. The specified radius value will not affect a polar pattern.
The actual radius of the series is determined by the origin of the selected component and guide curve PATTERNPOLAR based on their relation position.
Angle: Linear pattern
Defines the angle of a linear pattern. The angle of a symmetric pattern is 90 degrees, but you can also define another value.
Angle: Polar part pattern
Defines the angle at which the components will be set at equal distances.
Deleted
Defines which components are deleted from the pattern. The position of the component is given as XY coordinates inside parentheses. A period (.) is used to separate the X and Y coordinates. In the Deleted field, you can enter several components to be deleted one after another, for example (1.1)(1.3). The parent component is (1.1). You can define components to be deleted when creating or editing the pattern.
You can delete individual components from the pattern by entering one of the following in the Deleted field.
  • (n.1) - Delete the last component on the first row.
  • (n.n) - Delete the last component on the last row.
  • (n.*) - Delete the last component on every row.
  • (*.n) - Delete all components on the last row.
If you have deleted components by using the Delete function, the coordinates of the deleted components will be displayed in the Deleted field when you select the pattern for editing. You can edit the data by adding or deleting coordinates.
Edit a pattern by deleting the following components: (1.2)(2.1)(2.3)(3.2)(4.1)(4.3)(5.2).
In a polar pattern, the parent feature will have the coordinates (1.1). The numbering continues clockwise: (2.1)(3.1), etc.
Deletw a Component from a Pattern
Edited
When a feature pattern has been created of a local part, and a part other than the first one in the pattern has been edited, its coordinates are displayed in the Edited field just like the coordinates of a deleted component.
If there are asterisks inside parentheses in the beginning of the field (*.*), all parts of the pattern are separate instances. You can then edit each part of the pattern separately, including the first part of the pattern. If you clear the Edited field, all edited parts will be replaced with the original part.
Edit a Local Part in a Pattern
Replace Edited Local Parts with the Original Part
Pattern Location
Defines how the pattern is positioned in the assembly. Select one of the following options:
  • New Pattern - Click a location for the control part of the pattern in the assembly.Creating a Linear Pattern in One Direction by Defining the Number of Elements
  • Part from Pattern - Select a part from a pattern in the assembly.Pattern that is Associated with a Pattern in an Assembly
  • Face from Feature Pattern - Select a face from the feature pattern of the part.Pattern that is Associated with a Feature Pattern of a Part