Copy the Lines of a Drawing to the Sketch of a Part Model

General

You can copy elements of the drawing to:

• Active part model (part model in the working window)
• New part model.
• New part model in an assembly.

Copy lines to the sketch of a part model

1. Select the lines to use in the sketch from the Vertex drawing.
   • Drawings can include dimensions, but dimensions are not copied to sketches.
2. Select the context-sensitive function Copy to Model.
   • The program opens the dialog box Limit Selection.
   • The copied lines are shown in a preview image.
3. Select the projection to the sketch of which you want to copy the lines.
4. If necessary, select the layers whose lines you want to copy to the sketch.
5. If you want to limit the lines to be copied again, click Select Limits.
   • The drawing is displayed in the window where you click the elements to be copied with two corner points.
6. If necessary, select
   • Automatic constraints on or off.
     • The addition of the constraints may take some time if there is a large number of lines.
     • The following text will be displayed in the status bar during the addition: Automatic Dimensioning in Progress.
   • Select the guide curve on or off.
     • Creates a guide curve from the lines.
   • Select to explode into lines on or off.
     • Explodes the drawing into lines (cuts the lines into segments and arcs).
7. Select OK.
8. Click the model window or select Confirm (Confirm = V key, middle mouse button or the context-sensitive function OK).
   1. Click the model window to add the sketch to an existing model.
      • The model window must be visible, so the windows cannot be maximized.
      • The sketch opens at the default plane parallel to the projection you selected, so you cannot bind the sketch to the face of the model.
   2. Select Confirm to create a new part model.
      • The program opens the New Document dialog box.
      • Name the part, fill in the archive data and select the project, if necessary.
      • The sketch opens at the default plane parallel to the projection you selected.
9. Indicate a location for the sketch.
10. If necessary, modify the geometry of the sketch
    • Add constraints or remove automatically added constraints.
    • Adding Constraints
11. Continue modeling with a sketch-based feature.
    • If you selected Make a Guide Curve, the program will create a guide curve of the sketch when you exit the sketch mode with the OK function.
    • Features Based on a Sketch

Example

Copying the lines of a sheet metal part to the sketch of a part model

Use the clipboard to copy lines