Flange Feature Data

Sheet-Metal Design

General

  • The dialog box is related to the function Add Flange.
  • Add Flange

Dialog Box Options

Radius R
Defines the inner radius of the bend.
  • The value of the radius of the bending stop or the bending blade should be used as the inner radius.
Angle A
Defines the bend angle.

Length L
Defines the value of the length.

Formula
Defines the dimension’s variable.
Click
Click the button and select, for example, a length from the sheet-metal part.
Define the length L:
  • You can set the length to a surface or point. You can enter the offset value to the auxiliary menu field at the same time.
  • A positive offset value is outwards of the surface and a negative value is inwards to the surface when pointing a surface.
  • A positive value continues the bending feature past the point and a negative value leaves the bending feature shorter when pointing a point.
Define the Angle A:
  • Angle can be defined from a surface, point or line. By pointing a line, you set the direction parallel to the selected line. By pointing a surface, you set the direction perpendicular to the selected surface.
Alternatively, you can click a point outside of the model (B) by selecting the context-sensitive function OK or by pressing the middle mouse button to have the length of the sheet be determined by the line drawn by the cursor.
If the check box is selected, the chosen element is saved in the feature.
Select
Click the button to start the definition of a user-defined bend radius. The button is active only when a user-specific fitting has been defined.
Feature Type
Defines adding the bend as follows: The red color of the tip image shows the size of the part before adding the bend.
Add whole bend

Inside dimension

Outside dimension.

Cut type
You can choose the cut type when the type of the feature is
  • Inside dimension or
  • Outside dimension
You can select the cut type from the list:
  • Only edge

  • Edge + corner
    • The program cuts the edge and also the corners of the flanges next to it.
    • This option only gives the end result according to the image when Edge trim is not selected.

  • Whole end
    • This option only gives the end result according to the image when Edge trim is not selected.

Additional Dimensions
Figure 1: Definitions of the additional dimensions.
Side Angle
Define the values of the side angles into the Side angle A1 and Side angle A2 fields.
Figure 2: Example: A1 is 60 degrees and A2 is 10 degrees.
Take in
Define the values of the take ins into the Take in B1 and Take in B2 fields.
Figure 3: Example: B1 is 30 mm and B2 is 10 mm.
Note: The program will cut the edge only with cut type Only edge, if the feature has a additional dimensions Take in B1 or Take in B2.
Gap
Define the values of the gaps into the Gap C1 and Gap C2 fields.
Figure 4: Example: B1 and B2 are 20 mm, C2 is 10 mm and D is 10 mm.
Depth
Define the depth into the Depth D field.
Direction
Change the bending direction by clicking the button
Note: In many cases, it is not possible to combine this with function Edge trim. If you want to change the direction anyway, remove the trim first and create it again after changing the direction.
Edge trim
Select Edge trim if you want to automatically trim edges while adding a flange feature.

  • Automatic trimming uses the symmetric trim as a default.
  • The software creates two features in the feature tree. Flange and Edge trim. You can edit both features individually.
  • You can add selection Edge trim to an existing flange feature, if that specific flange feature is the last phase in the history.
  • If other features have already been modeled in the part, add the trimming of the edges as a separate work step.
Flanges
A list containing the selected flanges. You can select different feature parameters for each flange.
  • Select a flange from the list and enter values into the fields.
From the list, select the edge line whose parameters you wish to change and enter the values into the fields. You can add, change or delete selected elements on the list.
Add
Add new flanges, if necessary.
  • Select Add.
  • Click the edge, on which you wish to add the flange.
Change
If necessary, change the flange to another edge line.
  • Select the flange to be changed.
  • Select Change.
  • Click the edge, on which you wish to add the flange.
Delete
Remove any flange, if necessary
  • Select the flange to be deleted.
  • Select Delete or press the Delete key.